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hi,

In the drafting page, When ever i make a dimension it creates the size of the dimension text as 3.5mm which i way to big for the drawing. I need the size to be 2mm and its really annoying having to change it by hand every time. I'm unable to find where it sets the text size in the options menu.

How do i cahnge the default text size?

thanks

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hi,
you must change the default Text size in the ISO Standard xml File. Please use Tools Standard 

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HB

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Thanks for the reply. I have found the part you explaqined but the text size is set to 3.5 and it is greyed out and i am unable to change it.

How do i make it let me change the value?

Thanks

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Admin_1.jpg

Hi,

you have to start Catia in the admin-mode to make changes in ISO Standard xml File.

EDIT:

At first you have to make an right-click on the CATIA-Icon on your desktop. Now click on Properties (Screenshot: Admin_1)
Into the destination field (Screenshot: Admin_1) there is a variable called "-direnv". Copy the follwoing path to your explorer.
Into the folder there should be a file called CATIA.V5Rxx.Bxx.txt (depends on your CATIA release)
First make a backup from the file. Then open it with an ascii-editor.
Behind "CATReferenceSettingPath = " there should be no entries.

Now create a new folder (for example in the CATIA installation path). Copy the path of the folder and paste it into the environment file behind "CATReferenceSettingPath = ". This is now the temporary folder of the admin-mode environment.

Following make a copy/paste of the CATIA icon on your Desktop. Rename it for exapmle to "CATIA ADMIN"
open the icons properties -> links -> destination
Afterwards you have to change the line like my exapmle:

Original (should be left on the desktop to work with CATIA):
"C:\Programme\Dassault Systemes\B18\intel_a\code\bin\CATSTART.exe"  -run "CNEXT.exe" -env CATIA.V5R18.B18 -direnv "C:\Dokumente und Einstellungen\All Users\Anwendungsdaten\DassaultSystemes\CATEnv" -nowindow

Changed to start admin-mode (aditinal icon only to make changes in the environment. Not to work with models et cetera)
"C:\Programme\Dassault Systemes\B18\intel_a\code\bin\CATSTART.exe"  -run "CNEXT.exe -admin" -env CATIA.V5R18.B18 -direnv "C:\Dokumente und Einstellungen\All Users\Anwendungsdaten\DassaultSystemes\CATEnv" -nowindow

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MFG Daniel

Die KATJA ist halt doch nur ne zickige Französin

[Diese Nachricht wurde von denyo_1 am 19. Jun. 2008 editiert.]

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