---

After the restarting thermal->structural-  the output only for the thermal analysys, what is wrong?

Code:

---

/NOPR  ! Suppress printing of UNDO process
/PMACRO ! Echo following commands to log 
FINISH  ! Make sure we are at BEGIN level 
/CLEAR,NOSTART  ! Clear model since no SAVE found 
/input,menust,tmp,'',,,,,,,,,,,,,,,,1 
/GRA,POWER
/GST,ON
/PLO,INFO,3
/GRO,CURL,ON
/CPLANE,1 
/REPLOT,RESIZE
WPSTYLE,,,,,,,,0
/prep7
et,1,solid87       
mp,kxx,1,3                  ! Conductivity
BLOCK, 0,0.1, 0, 0.3, 0, 0.5
ESIZE,0.05
VMESH,ALL 
tunif,100
ASEL,S,AREA,,1 
NSLA,,1                ! SELECT TARGET NODES ON BIGGER CYLINDER
d,all,temp,500              ! Set outer wall temperature
allsel
ASEL,S,AREA,,2,6 
NSLA,,1                ! SELECT TARGET NODES ON BIGGER CYLINDER
sf,all,conv,2,100
allsel
physics,write,thermal    ! Write the thermal physics file
physics,clear            ! Clear all bc's and options
et,1,solid92
mp,ex,1,30e6              ! Define structural steel properties
mp,alpx,1,.65e-5
mp,nuxy,1,.3
ASEL,S,AREA,,1 
NSLA,,1                ! SELECT TARGET NODES ON BIGGER CYLINDER
d,all,all
ASEL,S,AREA,,2 
NSLA,,1                ! SELECT TARGET NODES ON BIGGER CYLINDER
cp,NEXT,ux,all
*GET,NC,NODE,,NUM,MIN  ! GET LOWEST NODE NUMBER (MASTER)
allsel
d,NC,ux,0.1
!
physics,write,struct    ! Write the thermal physics file
physics,clear            ! Clear all bc's and options
fini
!
/SOLU 
physics,read,thermal   
antype,trans,new
OUTPR,,LAST
OUTRES,,ALL
TIME,10     
DELTIM,1,1,2
NSUBST,20
SOLVE
FINI
!
/SOLU
physics,read,struct   
antype,stat,rest
ldread,temp,,,,,,rth   
SOLCONTROL,0
NLGEOM,ON
AUTOTS,ON
OUTPR,,LAST
OUTRES,,ALL
TIME,20     
DELTIM,1,1,2
NSUBST,20
SOLVE

---

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

on first sight:

if you do not intent to have structural solves before the thermal solve
you should remove: antype,stat,rest

------------------
Gruesse,
Frank Exius
IFE Deutschland  www.ife-ansys.de
Mo-Fr 9:00-18:00 Uhr durchgaengig

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

The idea to solve in cycle thermal structural, thus in any case it need:

antype,stat,rest

!,and than:

antype,trans,rest

!,and than:

antype,stat,rest

Possible you know how to transfer the mesh into another stage of the solution like
forces in ldread-comand?

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

cycle.txt

if you intent to cycle, construct a *DO *ENDDO loop
containing conditional *IF statements:

which makes the execution initially pass over
1) the script-snippet containing antype,stat,new

and subsequently makes the execution pass over
2) the script-snippet containing antype,stat,rest

cycle.txt (see attachment, please verify syntax)
is provided as a template only, for the structural part.
                  
------------------
Gruesse,
Frank Exius
IFE Deutschland  www.ife-ansys.de
Mo-Fr 9:00-18:00 Uhr durchgaengig

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

Hello,

I recently had some problems with restarting, as
ANTYPE,,REST
overwrites variables (including the loop counter) to their very first value.
That drove me mad.

I needed to write them into a file and get them back, after the restart.

Haven't checked your code yet, just an initial guss.

/EDIT:
Just checked your problem:
my guess has nothing to do with your problem.

Your problem really is none. Results are stored in different files (.rst for structural and .rth for thermal). If you would like to have a look the temperature distribution, you can do that in the GUI with
plot results -> nodal solution -> (scroll down) -> body temperature.

As far as I can remember:
If you would like to have the full thermal solution at hand you have to issue the appropriate PHYSICS command
PHYSICS,read,thermal
and then
->read results (sorry I'm a GUI user when it comes to postprocessing)
I can't check it right now, so please try by yourself and give me a feedback. I think of a workaround if it does not work.
EDIT/

Kind regards
Moritz

------------------
Moritz Oliver Gebhardt

[Diese Nachricht wurde von MGebhardt am 13. Nov. 2008 editiert.]

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

Thank you for the interests 

Thus the problem is simplier, it doesn't create *.rst at all!, but it's calculating structural part.
(I suppose it's not possible: antype,trans,new -> antype,stat,rest).

So how to create *.rst file (for my input-code)?

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

Ups,

should have read the other comments, starting with the first from IFE (I promise, I'll never answer posts shortly before going home again  )
Another try to convince you from
ANTYPE,STAT,REST
is wrong in the way you use it:

Both Physics domains are solved independently from each other. Just start the first structural run with
ANTYPE,STATIC,NEW

Later, when you call the next cycle you must use,
ANTYPE,STATIC,REST
but not the first time you call it.

This is independent from the thermal-model, which you did correctly start initially with ANTYPE,TRANS,NEW.

Just change this (as all the other posts have already suggested) and it should work.
Some hints:
-I did not understand, why you set a time for the structural analysis
-If you encover problems with your time counter when cycling through a *do-loop, just tell and also see my first post (Might only occur under LINUX).
Maybe its easier to start with issuing the solution procedures one by one, till you are statisfied. Then get the whole thing condensed in a loop.
-you can issue all /SOLU arguments before PHYSICS,WRITE. This keeps you from executing them in every cycle.

I'm slightly stunned that your ANSYS does not stop with a huge ERROR-Message.

Kind Regards
Moritz

------------------
Moritz Oliver Gebhardt

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP

---

OK, the idea to enforce ANSYS to solve thermal-structural task at the single database (avoid additional load transfer actions), as I understand it is possible only through the restart, thus how to do so?

Eine Antwort auf diesen Beitrag verfassen (mit Zitat/Zitat des Beitrags) IP